CATIA V5 - Generative Drafting:... in the ..\Generative Drafting\Data

Transcription

© 1997 – 2001 DASSAULT SYSTEMES
Generative Drafting
IBM Product Lifecycle Management Solutions / Dassault Systemes
Page 1
Tutorial Objectives
Description
? This Tutorial is an introduction to Generative Drafting.
Message
? To show how CATIA V5 allows the user to automatically generate
associative drafting from 3D mechanical parts produced with CATIA Version
5.
? To show a higher productive environment for drawings dress-up and
annotation
Duration
? 45 minutes
Product Coverage
? Part Design, Generative Drafting
Page 2
Tutorial Major Steps
Here are the different steps of this tutorial:
Step 1
? Prepare the drawing
Step 2
? Create main views
Step 3
? Use the Wizard to generate views
Step 4
? Create a Detail view
Step 5
? Create a Section view
Step 6
? Create Dimensions
Step 7
? Create a Breakout view
? Finish the drawing
Step 9
? Finishing
Note : in the ..\Generative Drafting\Data directory you can find several drawings named with the
different steps of this tutorial. If you have some difficulties or if you need to stop and continue sometime
later, you can load them at the end of each step to continue the tutorial.
Page 3
Step 8
Settings 1/2
Depending on your needs, you may have to modify the CATIA V5 settings (units, default
directory, visualisation parameters, etc…)
In order to use the appropriate settings for this tutorial, you have two possibilities:
1. Do the following operations (simplest one):
? Do not forget to put this folder (CATSettings) in read mode:
? Select the folder (CATSettings)
? Click mouse button 3 then click on Properties and
uncheck the Read-only Attribute
? Select all the files in the folder
? Click mouse button 3 then click on Properties and uncheck the Read-only
Attribute
2. Set them manually:
? Launch your CATIA V5 session and do the operations from page 32 onwards
Page 4
?BEFORE STARTING YOUR CATIA V5 SESSION:
? Copy or replace the directory ..\Generative Drafting\Data\CATSettings in:
For NT users
C:\Winnt\Profiles\XXXXX\Application Data\DassaultSystemes
For Windows 2000
C:\Documents and settings\Profiles\XXXXX\Application Data\DassaultSystemes
or XP users
For Windows
C:\Windows\Profiles\XXXXX\Application Data\DassaultSystemes
98 users
XXXX is the name used to log on to your computer
Settings 2/2
For this tutorial you also need to install a tooling and a material catalogue:
? Do not do this step if you have already done it in getting started or in a previous tutorial
? Copy the ..\Getting Started\Catalog.CATMaterial file under ..\Program
Files\Dassault Systemes\M07\intel_a\startup\materials\French directory
Files\Dassault Systemes\M07\intel_a\startup\materials\German directory
Files\Dassault Systemes\M07\intel_a\startup\materials\Japanese directory
Files\Dassault Systemes\M07\intel_a\startup\materials directory
? Answer Yes in order to replace the old catalogue
You are now ready to launch your CATIA V5 session
Page 5
Step 1: Open the Part
Opening Files
? Close all the windows in CATIA
? Open the file Spindle.CATPart under
the … \Generative Drafting\Data directory
?NB: There are several ways of
opening the files
?In the Browse window, check the
Show Preview option
?Select the Spindle.CATPart file
?Click on Open button
?Answer Yes to the question
because some libraries are not
installed on this CATIA demonstration
mode
Page 6
Step 1: Open a new drawing
Opening files
? Select Start + Mechanical Design +
Drafting in the menu bar to access the
Drawing workbench
? Check that the first layout is
selected
?In the New Drawing Creation
window, click on the Modify button
?Choose ANSI for the Standard and
C ANSI for the Format
?Validate by clicking on OK in the
New Drawing window
?Validate by clicking on OK in the
New Drawing Creation window
? A new drawing window is opened
Page 7
Step 1: Add the Company Background
Adding the template
?Select File + Page Setup in the Menu bar
?In the Page Setup window, click on Insert
Background View…
?Click on the Browse button in the displayed
window
?Browse your hard disk in order to find and
select the DS_Template.CATDrawing file
?Click on the Open button
?Click on Insert button in the Insert element
into a sheet window
?Click OK in the Page Setup window
? The frame is inserted in the Background
view
? If you want to have access to this
background layer, select Edit + Background in
the Menu bar. Before going to the next page,
return to the Working view by selecting Edit +
Working Views in the menu bar
Page 8
Step 1: Change the Scale
Modification of the scale
? You can access the properties of the
whole sheet
?Click MB 3 (Mouse Button 3) on
Sheet.1 in the specification tree
?Select Properties
?In the Global scale field, key in
1/32
?Click on OK to validate
? The whole sheet will now have this
new scale value
?Click on the Snap to point icon on
the bottom toolbar to deactivate it
? The icon should turn blue
Page 9
Step 2: Start the Drawing
Creating the front view
? You will now learn how to create a front view
? Click on the Front view icon on the right
Toolbar
? Select Window + Tile horizontally in the
menu bar
? Click in the bottom window and
OUTSIDE of the geometry
? Drag the mouse cursor over the various
3D planes on the specification tree
WITHOUT clicking
? If you click on the plane you will create the
corresponding 2D view. To delete a created
view, refer to the next page
? The preview window shows you the
result
? Click the front face of the Spindle
? If you have trouble selecting it, don’t
hesitate to zoom in before clicking
Page 10
Step 2: Start the Drawing
Orientating the front view
? You can rotate the views before creating them
? Click on the arrows of the compass to
orientate the front view
? When you have the view positioned as
shown here, click anywhere on the grid
? To have the same orientation you should
click 3 times on the left rotation arrow (the
inside circular arrow)
? After a few seconds, the view is created
? If you have failed, you need to delete the
view and re-do it. (See page11 on how to
delete a view).
? Select and drag the text box, placing it
under the front view as shown
? Maximise the drawing window
? Zoom out to see the whole page
? Select the front view frame and drag it to
position it as shown
Page 11
Step 2: Generate some other views
Creating a projection view
? How to create a left view
?Click the Projection view icon behind the
Front view icon
? You have to click on the black arrow at the
bottom right of the front view icon
?Drag the projection view around the front
view to preview the different projections you
could create
?Now position the projection view as shown
on the right and click MB1
? Another way to create views
?Delete the views by clicking MB3 on the
frame (and not inside the frame) of both
views and then selecting the Delete function
? Another way is to select a view and use the
Delete key of the keyboard
Page 12
Using the Wizard
? You can generate the views one by one as you
did in the last pages or use the wizard creation
?Click on the Wizard icon in the View
toolbar.
?Click the different vertical icons to preview
what you could create, then finish by selecting
the 3rd configuration
? By selecting this icon, you can create the
Front, the Left and the Top views
? If you want to delete a specific view, click
MB3 on the view
?Click on the Next button
Page 13
Using the Wizard
? You can also choose the view by view
selection instead of a whole or
complementary configuration
?Click on the Isometric view icon
and drag the preview result to
position it as shown then click MB1 to
position it
?Key in 1 for the Minimum distance
between each view
?Click on the Finish button
?Reduce the drawing window
Page 14
Using the Wizard
?Zoom in and click MB1 on the
Front face
?Maximize the drawing window
?Rotate the views using the
Compass as previously explained
?When satisfied, click anywhere on
the sheet to create the views
?Move the Front view by dragging
its frame
? The other views will move
automatically
?Move another view
? The other views will not move
Page 15
Step 4: Create a Detail
Creating a detail view
? How to create a detail view
?Zoom in on the Front view (check that this
view is active)
?Click the Detail view icon
?Click once in the place shown
? A circle is generated showing you the area of
the detail view
?Drag the mouse to change the radius
?Click the sheet when the radius is as shown
?Zoom out to see the top left corner of the
sheet
?Drag the mouse to the top left side of the
sheet and click there
? The detail is created here with a 1:16 scale
factor (x2)
Page 16
Step 4: Create a detail
Creating a detail view
?Click MB3 on the Detail view blue
frame and select Properties
?Key in 8 instead of 16 in the Scale
field
?Uncheck the Centre Line option
?Validate the properties by clicking
OK
?Zoom out and reposition the detail
view
Page 17
Step 5: Create a Section
Creating a section view
? How to create a section view
?Double-click the frame of the Detail A view to
activate it
?Zoom in on the Detail A view to see the hole
?Click the Offset Section view icon
?Pass the cursor on the circle to detect the
coincidence constraint then click
? Automatically you will define a section profile
that passes through the circle centre
?Draw a vertical line as shown
? You should see the line turning blue when it is
vertical
?Double click to end the profile creation
?Zoom out to see the whole sheet
?Drag the section view on the left and click
MB1 to create it
?Move the Section view
Page 18
Step 6: Create dimensions
Generating dimensions
? You can automatically generate dimensions on one of
the views
? Zoom out and double-click MB1 on the blue frame
of the Section view
? The colour of the frame changes to red. This means
the Section view is now the active window
? Key in 0.08 in the font size field
? Click on the Thread Dimension icon behind the
Dimension icon
? Select the top line that represents the thread by
clicking MB1
? the thread dimensions are displayed
? Select dimension value to move and drag it to the
left or right as shown
? Multi select the two values (use CTRL key) and
click MB3 then MB1 on Properties to customise
extension line.
? Click on the Extension Line tab then Key in 0 in as
blanking value.
? Click OK to validate the modification
Page 19
? You can automatically generate dimensions on
one of the views
?Zoom out and double-click MB1 on the blue
frame of the Bottom view
? The colour of the frame changes to red. This
means the Bottom view is now the active
window
?Click on the Dimension icon
?Select the bottom line by clicking MB1
? A diameter dimension is displayed
?Without clicking, drag the mouse. When the
dimension is correctly positioned, click MB1
? If you make a mistake, delete it with Delete
key of the keyboard or with the contextual menu
?Drag the value to the right of the dimension
line
?Click on the dimension arrow to reverse its
orientation
?Click anywhere to finish
Page 20
? Click on the Dimension icon
? Select the bottom line again
? Select the top line
? The value displayed automatically
switches from a diameter value to a length
value
? Drag and position the dimension as you
did before
? Click anywhere to finish
? Click MB3 on the dimension and select
Properties
? Select the Extension line Tab then key in
0 in as blanking value
? Click Ok
? On the dimension value, click MB3 and
select Set as Default
? Select the Only User Default Properties
option
? Now you will re-use automatically the
properties defined for the next length
dimension creation.
Page 21
?Behind the Dimension icon, select the
Stacked Dimension icon
5
?Select the bottom line again
?Then select the next 4 lines as shown
? They have to be selected in the right order
?Without clicking, drag the mouse and
position the dimensions as shown here
? If you drag one dimension, the others follow
?NB: If you click MB1, you can move each
dimension individually.
4
3
2
1
? You will note that you have the same
properties as the last length dimension created
(text size, blanking value)
?Validate the creation by clicking MB1
? You can then move the dimensions one by
one so that they do not overlap
Page 22
Using automatic generation
? You can also generate 3D dimensions using
the wizard
? Zoom in on the Detail view
? Double-click the frame of the Detail view
to activate it
? The frame should turn red
? Click anywhere on the sheet to deselect
it
? In the Menu bar, select Tools +
Dimension generation + Filters…
? Select the Detail view frame in the 2D
sheet (this is very important if you don’t
want to generate the dimensions in all
the views)
? Click the Sketcher wireframe
constraints option in the Dimension
Generation Filters window
? Click OK
Page 23
?Click the Generating Dimensions
icon in the Generation toolbar.
?Select the Detail frame again
? Some dimensions are
automatically generated
?Reduce the Drawing window
?Check Generated constraints in
the Generated dimensions analysis
window
? The corresponding dimensions are
displayed in the 3D view
?NB: Checking different options will
generate different dimensions.
?Click OK to close
Page 24
?Maximise the drawing window
?Zoom in on the Detail view
?Delete the dimensions you don’t
want to see
?Move and place the others as you
have done before
? You should be an expert by now…
Page 25
Step 7: Create a Breakout view
1
Creating a Breakout view
2
? You will learn how to generate a Breakout view
?Double-click on the Front view frame to
make it active
?Click on the Breakout View icon behind the
Broken View icon
?Click on the axis (1)
?Click on the Centre when you have the
double-circle (2)
5
?Click on the other axis (3)
?Move the mouse to the left and click MB1
when the perpendicular symbol and the vertical
dotted line are displayed (4)
?Click on the first point to close the profile (5)
4
3
Page 26
Creating a breakout view
? A preview is displayed to show you
the depth limit of the broken view. This
limit is represented by a green line
?Zoom out to see the Right view
?Move the mouse over the vertical
edges in that Right view
? You will see the dynamic preview
1
?Click on the edge you need
? As shown (1)
?Click OK in the Preview window to
validate
? You can see the result in the Front
view
Page 27
Creating a breakout view
? CATIA gives you the option to
propagate this breakout view to
another view.
?Click MB3 on the Front view frame
+ Front view object + Apply Breakout
To
?Select the Isometric view frame
? The breakout view now appears in
the Isometric view.
Page 28
Step 8: Change Standard
Changing Standards
? CATIA gives you the option to
switch the standards if you want to
exchange drawings with a supplier or
subcontractor from another country.
?In the File menu, select Page
Setup
?Select the ISO Standard and the
A2 ISO format
?Click OK
? You can see that all dimensions
automatically change to an ISO
representation.
Page 29
Step 9: Finishing
Finishing steps
? You can remove the view frames
?Select the Detail view in the tree
?Click MB3 + Properties
?Click the Frame option to deselect
it
?Click OK to validate
Page 30
This is what you can create
Page 31
Manual Settings
Page 32
Settings
Tools/Options
? Select Tools + Options menu
? Under General select Parameters on
the tree
?Select Units tab
?Select the Length line
?Select Inch (in) in the pull down
menu
Page 33
Settings
Tools/Options
? Under Mechanical Design select
Drafting on the tree
?Select Generation tab
?Select the options as shown
?Click OK to validate
Page 34
CONGRATULATIONS
Page 35

CATIA V5 - Generative Drafting:... in the ..\Generative Drafting\Data

Transcription

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